Sheet metal settings help · 日本語 · Printable PDF (Japanese, 4 pages)
Convert to sheet metal: selection and workflow
1. What this command does
Recognize flat plate registers an existing uniform flat solid as a sheet-metal part. It stays in the same model space and position, retaining its outline, physical thickness and through holes. Apply adds the information used by subsequent sheet-metal operations; it does not bend or resize the plate.
Use it for a flat solid made with regular extrusion tools or imported from another file. A part made with Base plate already has sheet-metal information. For an outline without a solid, use Base plate instead.
2. Select the solid and base face
- Open Convert to sheet metal.
- Use Pick in CAD beside Solid to select the whole plate.
- Use Pick in CAD beside Base face to select a broad planar face on that same plate. Either the top or bottom face can be used.
The base face is used to measure physical thickness. Avoid narrow side faces, cylindrical hole walls and faces on another part. On a box-shaped solid, a side face can cause another dimension to be interpreted as thickness. This selection does not specify the next bend's position or angle.
Changing the solid clears the previous base-face selection. Select the solid first, then its base face.
3. Thickness source, K factor and Apply
| Field | Meaning and use |
|---|---|
| Thickness source: Detect automatically | The usual choice. The thickness field is disabled. Apply measures the actual geometry. The grey value shown during selection is an initial or loaded condition, not a live measurement. |
| Thickness source: Specify value | Enter the intended thickness. Apply checks that it matches the geometry. A mismatch is rejected. This does not make the plate thicker or thinner. |
| K factor | Used for the allowance of subsequent bends. K=a/t, where a is the distance from the future inside surface to the neutral layer. It does not change the flat plate during recognition and is not selected automatically from a material name. |
- Normally choose Detect automatically and check the K factor.
- Click Apply. Recognition and geometry checks run at this point.
- After success, click Close and save the drawing.
The registered thickness comes from the geometry. To inspect it, open Sheet metal settings, choose Selected sheet metal part and select the part. Length inputs use the units shown beside the fields. K is dimensionless.
4. Supported and unsupported shapes
These are representative section views. The command checks a closed solid, matching opposing faces and boundaries, and uniform thickness. Through holes and through notches are supported when the plate meets those conditions. Steps, taper, or bevels and rounds across the thickness can prevent recognition in this initial implementation.
This is not automatic unfolding of a part already bent in another CAD system. Start with a flat plate, register it, and create bends with JDesignCAD's sheet-metal commands.
Ripping a corner of a box does not convert it into a folded sheet-metal part. Rip cuts the geometry of an ordinary solid. Conversion into unfoldable sheet metal requires a fixed face, bend locations, thickness, inside bend radius and bend allowance, together with the required bend geometry and reliefs. A layout with a fixed bottom and four opening side walls needs rips at all four vertical wall-to-wall corners. The Convert box / L / U-shaped solid mode supports a uniform rectangular bottom with one to four perpendicular walls. Full-height corner seams are supported; holes, steps and existing bend radii remain unsupported. See the illustrated box conversion workflow.
5. Next operations and troubleshooting
Flat solid → Convert to sheet metal → Edge flange / Bend along line → Unfold → Through cuts in planar regions → Refold
Successful recognition does not change the appearance. It registers sheet-metal data in the same model space, without adding another part. Undo reverses the operation. A failed check preserves the original solid.
| Symptom | What to check |
|---|---|
| Cannot select the base face | Select the solid first, then a broad planar face on that same part. |
| Uniform flat plates only | Check for bends, steps, blind holes, taper or an open surface instead of a closed solid. |
| Specified thickness does not match | Check the value, displayed unit and base face. Use automatic detection if the thickness is unknown. |
| Registered thickness is unexpected | Check whether a narrow side face was selected. Also verify the actual dimensions and imported scale. |
| No visual change after Apply | This is expected: recognition registers information. Create the bend with the next command. |
Do not run recognition again on an unfolded sheet-metal part. The current command starts fresh sheet-metal information and does not retain existing bend history. After making through cuts in the unfolded part, use Refold directly.